This example Demonstrates 2 different ways to add component into the assembly tree using SOLIDWORKS API.

  • Traditional way to add component via AddComponentX SOLIDWORKS API requires the model to be loaded into the memory. Otherwise the operation fails.
  • More advanced way is to use the AddComponents SOLIDWORKS API. This method allows batch insertion of different components without the need to open the model beforehand.

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Dim swApp As SldWorks.SldWorks
Dim swMathUtils As SldWorks.MathUtility
Dim swAssy As SldWorks.AssemblyDoc

Sub main()

    Set swApp = Application.SldWorks
    Set swMathUtils = swApp.GetMathUtility
    Set swAssy = swApp.ActiveDoc
    If Not swAssy Is Nothing Then
        Dim comp1Path As String
        Dim comp2Path As String
        comp1Path = swApp.GetCurrentMacroPathFolder() & "\Part1.sldprt"
        comp2Path = swApp.GetCurrentMacroPathFolder() & "\Part2.sldprt"
        Dim swComp As SldWorks.Component2
        'Following API call will fail as it is required to have the model loaded into the memory
        Set swComp = swAssy.AddComponent4(comp1Path, "", 0, 0, 0)
        Debug.Assert Not swComp Is Nothing
        'Loading model invisibly
        swApp.DocumentVisible False, swDocumentTypes_e.swDocPART
        swApp.OpenDoc6 comp1Path, swDocumentTypes_e.swDocPART, swOpenDocOptions_e.swOpenDocOptions_Silent, "", 0, 0
        swApp.DocumentVisible True, swDocumentTypes_e.swDocPART
        'Now this API call succeeded
        Set swComp = swAssy.AddComponent4(comp1Path, "", 0, 0, 0)
        Debug.Assert Not swComp Is Nothing
        Dim strCompNames(0) As String
        Dim vTransformData As Variant
        Dim vComps As Variant
        strCompNames(0) = comp2Path
        vTransformData = swMathUtils.CreateTransform(Empty).ArrayData
        'It is not required to load document into memory if this method is used
        vComps = swAssy.AddComponents(strCompNames, vTransformData)
        Debug.Assert UBound(vComps) <> 1
        MsgBox "Please open or create assembly"
    End If

End Sub