Set BOM Quantity (Unit Of Measure) property using SOLIDWORKS API
This example demonstrates how to modify the BOM quantity field in the properties dialog using SOLIDWORKS API.
This option allows overwriting the quantity value of the component in the BOM table
In order to change this property it is required to set the hidden UNIT_OF_MEASURE custom property via ICustomPropertyManager SOLIDWORKS API interface.
Dim swApp As SldWorks.SldWorks Dim swModel As SldWorks.ModelDoc2 Const BOM_QTY_PRP_NAME As String = "UNIT_OF_MEASURE" Const QTY_PRP_NAME As String = "Qty" Sub main() Set swApp = Application.SldWorks Set swModel = swApp.ActiveDoc If Not swModel Is Nothing Then Dim swCustPrpMgr As SldWorks.CustomPropertyManager Set swCustPrpMgr = swModel.Extension.CustomPropertyManager("") Dim bomQtyPrp As String swCustPrpMgr.Get3 BOM_QTY_PRP_NAME, False, "", bomQtyPrp Debug.Print bomQtyPrp swCustPrpMgr.Add2 BOM_QTY_PRP_NAME, swCustomInfoType_e.swCustomInfoText, QTY_PRP_NAME swCustPrpMgr.Set2 BOM_QTY_PRP_NAME, QTY_PRP_NAME Else MsgBox "Please open model" End If End Sub